|
|
Too many SOT 23s |
Post Reply 
|
| Author | |
DaveCowl 
Advanced User 
Joined: 18 Oct 2012 Location: Santa Clara, CA Status: Offline Points: 161 |
 Post Options
 Thanks(0)
 Quote Reply
 Topic: Too many SOT 23sPosted: 30 Oct 2012 at 7:17pm |
|
I am sure that this has been answered before but I can't seem to find it. I have run up against two (only 2?) different SOT23-6 footprints (currently Maxim vs TI) with the same height and such so that the names of the library entries are the same. FPX seems to keep both of them there... but what is going to happen if I do a mass export of land patterns? It looks like I can manually edit the Footprint Name, so perhaps that is the place to start? What is the accepted norm for naming (I recall A, B, etc. has fallen out of favour...). Cheers!
|
|
 |
|
|
|
|
Tom H
Admin Group 
Joined: 05 Jan 2012 Location: San Diego, CA Status: Offline Points: 5717 |
Post Options
Thanks(0)
Quote Reply
Posted: 30 Oct 2012 at 7:22pm |
|
The object is to use the FPE FPX as a resource to Copy/Paste into you personal FPX. Your Company FPX should only contain parts your company uses.
|
|
|
|
|
DaveCowl
Advanced User
Joined: 18 Oct 2012 Location: Santa Clara, CA Status: Offline Points: 161 |
Post Options
Thanks(0)
Quote Reply
Posted: 31 Oct 2012 at 9:39am |
|
I understand that - both of these parts are on the same board.
Essentially the same part, just with quite different tolerances and pin dimensions for 'b' and 'L'. |
|
|
|
|
Tom H
Admin Group
Joined: 05 Jan 2012 Location: San Diego, CA Status: Offline Points: 5717 |
Post Options
Thanks(0)
Quote Reply
Posted: 31 Oct 2012 at 10:08am |
|
The variances in "b" and "L" will generate a different pad size and spacing. But the component Maximum Height value are different and that differentiates the footprint name.
|
|
|
|
|
DaveCowl
Advanced User
Joined: 18 Oct 2012 Location: Santa Clara, CA Status: Offline Points: 161 |
Post Options
Thanks(0)
Quote Reply
Posted: 31 Oct 2012 at 11:32am |
|
Actually the maximum height are identical. Hence the problem with naming... I guess I could change one to be 0.01 mm different, which would result in a different name...
|
|
|
|
|
Tom H
Admin Group
Joined: 05 Jan 2012 Location: San Diego, CA Status: Offline Points: 5717 |
Post Options
Thanks(0)
Quote Reply
Posted: 31 Oct 2012 at 11:51am |
|
IPC-7351C will recommend the following -
n The
original IPC-7351 footprint naming convention does not include component
tolerances, thermal pad sizes, BGA Ball sizes or various pin assignments into
account. Therefore, the same component with different tolerances can produce a
different land size and spacing with the same footprint name.
n A
footprint name of SOP50P710X120-14N can have version A, B, C, D which do
not indicate the variances.
n As
you add parts to your library and you encounter a duplicate footprint name due
to Thermal Pad size, Terminal Length Tolerance or Ball Size
1. Thermal Tab Size = SOP50P710X120-14NT300 ·
T300 = Thermal
Pad 3.00 mm
2. Lead Length Tolerance = SOP50P710X120-14NL50 ·
L50 = Lead Length
= 0.50 mm
3. Ball Size = BGA121C50P11X11_600X600X100NB23 ·
B23 = Ball
Diameter 0.23 mm
n For
component mfr. recommended footprint drop the environment level character after
the pin qty. - SOP50P710X120-14
|
|
|
|
|
DaveCowl
Advanced User
Joined: 18 Oct 2012 Location: Santa Clara, CA Status: Offline Points: 161 |
Post Options
Thanks(0)
Quote Reply
Posted: 31 Oct 2012 at 12:20pm |
|
Ok great thanks.
The 'L50' type of option to define lead length should be adequate to differentiate the two. Cheers!
|
|
|
|
|
Post Reply
|
|
| Tweet |
| Forum Jump | Forum Permissions You cannot post new topics in this forum You cannot reply to topics in this forum You cannot delete your posts in this forum You cannot edit your posts in this forum You cannot create polls in this forum You cannot vote in polls in this forum |
Topic Options