Import to CircuitStudio

In my experience, you need to manually add the step file as it isn't added by default. 

However, exporting from PCB with the Altium Nexus settings and then open and run the script in CS seems to automatically load both the footprint and the 3d model. 

I've also found that the CS export/import seems to end up with surface mount pads as "multi-layer" and one of the footprint outlines (sorry, can't remember which one) ended up as a bottom layer, not top. This doesn't happen with the Altium Designner/Nexus export/script run method. 

The only problem is that scripts aren't officially supported in CS (but you can still run them via the search field at the top right).

Just edit exported *.pas file as follows:

 

Procedure CreateAPCBLibrary(Zero : integer);
Var
    View     : IServerDocumentView;
    Document : IServerDocument;
    ///my edit starts here
    Kind     : TDynamicString;
    ///my edit ends here
Begin
    If PCBServer = Nil Then
    Begin
        ShowMessage('No PCBServer present. This script inserts a footprint into an existing PCB Library that has the current focus.');
        Exit;
    End;
    ///my edit starts here
    Kind := 'PCBLib';
    Document := CreateNewDocumentFromDocumentKind(Kind);
    ///my edit ends here
    CurrentLib := PcbServer.GetCurrentPCBLibrary;
    If CurrentLib = Nil Then
    Begin
        ShowMessage('You must have focus on a PCB Library in order for this script to run.');
        Exit;

 

 

Then in CS open document *.prjscr , double-click on *.pas, type "run" (without quotes) in search field and press enter.

New library file (*.PcbLib) will be created and new part will be indserted into it. 3D model will be added too.